Macro Templates

Drilling Macro

Rotary Tools

They are called to do central drilling with vertical mill or live tools, using rotary tools. They take care of the following machining.

  • Right Tapping
  • Left Tapping
  • Reamering
  • Deep Hole Drilling
  • Spot Drilling
  • Boring
  • Counterboring

Static Tools

They are called to do central drilling with the lathe, using static tools. They take care of the following machining.

  • Right Tapping
  • Left Tapping
  • Reamering
  • Deep Hole Drilling
  • Spot Drilling

Repeat macro template for every drill point

If your machine need to recall macro for every drill point, you need to set to check the

[Repeat drilling macro for every point] property ( use the search field to find this property ).

Most probably you have to adjust the macros template accordingly to your need.

Example 1 Deckel FP6NC - Dialog 11

Here the required drill macro code : 

G83 X16.795 Y29.09 TI-22. MI10.
G83 X-16.795 Y29.09 TI-22. MI10.
G83 X-33.59 Y0. TI-22. MI10.
G83 X-16.795 Y-29.09 TI-22. MI10.
G83 X16.795 Y-29.09 TI-22. MI10.
G83 X33.59 Y0. TI-22. MI10.

To get this , you need to update the [Deep hole drilling] and other templates in this way :

G83{COO_X}{COO_Y}TI{TOTAL_INCRE_Z}MI{STEP_VALUE}{FEED_CODE}

If needed , add {COO_X} and {COO_Y} in the [Drilling Template - Always Repeated Code] code list .

Example 2 Deckel Dialog 4

Here the required drill macro code : 

G0 X0.0 Y0.0 Z2.0
G82 F76 S+600 Z-10.0 Z-1.0 Z0.5
G0 X10.0 Y0.0 Z2.0
G82 F76 S+600 Z-10.0 Z-1.0 Z0.5

First change the default value for this 2 property :

  • Spindle CW : M3 S+
  • Spindle CCW : M4 S-

Then change the template for deep hole drilling :

G0{COO_X}{COO_Y}{SECURE_Z_CODE}
G82{SPINDLE_ORIENTATION}{SPEED_VALUE}Z{TOTAL_INCRE_Z}Z{STEP_VALUE|-1}Z.5

As before , if you need to force some {TAGS} to be always repeated , insert it in the [Drilling Template - Always Repeated Code] property .

Example 3

Customizing macro for deep hole drilling , for DYNAPTH lathe machine :

1) Change template for [Lathe Deep Hole Drilling] with

" (7) {ABSOLUTE_Z_DEPTH}W{STOCK_END_VALUE}{STEP_CODE}V{FEED_VALUE}{DWELL_CODE} "

2) Change the char code for DWELL_CODE and STEP_CODE

Type "step" in the search field of post-processor dialog and change [Macro Step (Peck] Code] from Q to K

Similarly Type "dwell" and change :

  • [Macro Dwell Code] from P to L
  • [Macro Dwell Mode] from millisecond to second

3) Now the output code for deep hole drilling macro is :

  (7) Z-48.W0.K14.V0.168L0.5

LATHE Threading Macro

To customize the threading macro for lathe, insert threading in the serch field , then edit property [Macro - Lathe Threading]

DICTIONARY CODES OUTPUT
PITCH_CODE [Code Feed] + value of thread pitch . F2.5
PITCH_VALUE Only numeric value of thread pitch . ex. 2.5
START_Z_CODE Start Z Code ( ABSOLUTE)
START_Z_VALUE
END_Z_CODE End Z Code ( ABSOLUTE)
END_Z_VALUE
FIRST_DIA_CODE First Thread Step Diameter Value. X40
FIRST_RADIUS_CODE First Thread Step Radial Value. X20
PLACEHOLDER_DIAMETERS_LIST Placeholder for step list X40 X39.5 X38 ...
MAJOR_DIAMETER_VALUE
MINOR_DIAMETER_VALUE
THREAD_ANGLE ex : 60° for metric, 55° for Withworth
STEP_COUNT Number of step necessary to create the thread
THREAD_DEPTH_VALUE full thread depth
THREAD_PEAK_DIA The thread peak offset from the drive line. Negative I values are external threads, and positive I values are internal threads
THREAD_PEAK_RADIAL Same as above, but radial values
FIRST_INCREMENT_DIA Initial Cut Depth or First Step Depth
FIRST_INCREMENT_RADIAL Same as above, but radial values

Example

Threading macro template for Emcotronic TM-02

Set this string as [Thread Template]

  1. G85 X{MAJOR_DIAMETER_VALUE} {END_Z_CODE} D3 {STEP_COUNT} D4 2 D5 {THREAD_ANGLE_VALUE} D6 {THREAD_DEPTH_VALUE|1000} D7 6 F{PITCH_VALUE}

  2. Set 1000 as [Feed SYNC Multiplier]. In this way the feed values are expressed in 1/1000 mm .

Example 2 - M30 x 2 - Linux CNC

G76 Macro Reference Page

Lathe Threading Template:

G76 P{PITCH_VALUE} {END_Z_CODE} I{THREAD_PEAK_DIA}  J{FIRST_INCREMENT_DIA} K{THREAD_DEPTH_VALUE} H1 L2 E1

Output:

G76 P2. Z-19. I-2. J0.522 K1.26 H1 L2 E1

Expand canned cycles

From version 2.1.0.241

Not in all controller are available canned cycles, to support also this machines is possible to expand the canned cycles in simply movementes.

To obtain this you need to delete the canned cycles template from post processor dialog.

Note: Tapping cycle not supported yet.

Thread cycle example :

By default is used the G92 macro, here the template :

G92{FIRST_DIA_CODE}{END_Z_CODE}{PITCH_CODE}
{PLACEHOLDER_DIAMETERS_LIST}

and the output g-code is like this :

G92 X9.535 Z-15. F1.5
X9.15
X8.798
X8.528
X8.301
X8.1

Now delete the thread cycle template from post processor in this way :

The output will become like this :

...
X9.535
G32 Z-15. F1.5
G0 X12.
Z1.5
X9.15
G32 Z-15. F1.5
G0 X12.
Z1.5
X8.798
G32 Z-15. F1.5
G0 X12.
Z1.5
X8.528
G32 Z-15. F1.5
G0 X12.
Z1.5
X8.301
G32 Z-15. F1.5
G0 X12.
Z1.5
X8.1
G32 Z-15. F1.5
G0 X12.
...

Deep hole drilling example :

Default Template :

G83{ABSOLUTE_Z_DEPTH}{POINT_R_CODE}{STEP_CODE}{FEED_CODE}
G80

Default Output :

G83 Z-30. R0.Q10. F0.12
G80

Now deleted the template , for lathe in this case :

And this will be become the output :

X0.
G1 Z-10. F0.12
G0 Z2.
Z-9.
G1 Z-20. F0.12
G0 Z2.
Z-19.
G1 Z-30. F0.12
G0 Z2.

results matching ""

    No results matching ""